UGS & PicSender issue

Software
1

I switched over today from Estlcam. Although I love the simplicity and function of the Goode sender I’ve found that carves are extended (time wise) when compared to the other senders. I guess it has to do with the built in slowing based on the max speed of your slowest axis. It is a top notch program but the time induced was considerable. Maybe I just didn’t set it up correctly. Who knows.

Anyhow, I’m using VCarve Pro to generate my toolpaths and using the Mach3 Post processor. Problem #1: When sending the code through UGS the spindle shuts off at every raise and starts again on the lower. I’m unable to see any speed commands that would trip my PWM triggered outlet but a voltmeter show it going from 0-5-0 volts resulting in the above.

Problem 2: in Picsender I keep getting notified of a problem in the code in line 13 or before. There was a M6T1 command but I removed it. Still no happy.

Any thoughts from the masters?

A snippet of the code:
( Date Created = Wednesday October 18 2017 )
( Material Width 7.125 inches )
( Material Height 7.500 inches )
( Material Thickness 0.760 inches )
( Home X/Y = Bottom Left Corner )
( Z Zero Position = Material Surface )
G17
G20
G90
G0Z2.3010
G0X0.0000Y0.0000S16000M3
G0X0.5690Y1.0977Z0.2500
G0Z0.0500
G1Z-0.0428F30.0
G1X0.5690Y1.1032Z-0.0426F100.0
G1X0.5714Y1.1162Z-0.0419
G1X0.5755Y1.1269Z-0.0409
G1X0.5810Y1.1361Z-0.0399
G1X0.5896Y1.1458Z-0.0386
G1X0.5980Y1.1522Z-0.0375
G1X0.6097Y1.1580Z-0.0361
G1X0.6194Y1.1611Z-0.0353
G1X0.6336Y1.1632Z-0.0344
G1X0.6503Y1.1632Z-0.0344
G1X0.6690Y1.1604Z-0.0343
G1X0.6890Y1.1551Z-0.0345
G1X0.7068Y1.1487Z-0.0345
G1X0.7243Y1.1409Z-0.0344
G1X0.7436Y1.1309Z-0.0345
G1X0.7675Y1.1401Z0.0000
G1X0.7436Y1.1309Z-0.0345
G1X0.7547Y1.1007Z0.0000
G1X0.7436Y1.1309Z-0.0345
G1X0.7289Y1.1386Z-0.0342
G1X0.7097Y1.1474Z-0.0343
G1X0.6907Y1.1546Z-0.0345
G1X0.6711Y1.1600Z-0.0343
G1X0.6532Y1.1630Z-0.0343
G1X0.6403Y1.1635Z-0.0346
G1X0.6299Y1.1629Z-0.0347
G1X0.6172Y1.1605Z-0.0354
G1X0.6048Y1.1560Z-0.0367
G1X0.5958Y1.1507Z-0.0377
G1X0.5873Y1.1437Z-0.0391
G1X0.5794Y1.1338Z-0.0402
G1X0.5734Y1.1221Z-0.0414
G1X0.5698Y1.1093Z-0.0422
G1X0.5690Y1.0985Z-0.0427
G1X0.5703Y1.0882Z-0.0425
G1X0.5744Y1.0763Z-0.0422
G1X0.5818Y1.0634Z-0.0410
G1X0.5905Y1.0522Z-0.0401
G1X0.6031Y1.0391Z-0.0392

3

I will certainly give it a try in the morning. Thanks for the comment!

4

Made no difference. I’m still getting the Line 13 error in PicSender and UGS keeps continually turning my spindle on and off.

Laser is working fine though!

5

The error message displayed by PicSender is being reported by grbl to PicSender. What grbl version are you using? Please post your grbl settings, too. You may have a corrupted grbl install (just a guess). Your code snippet runs fine on my test rig with standard grbl 1.1f.

1 Like
6

The mach3 post processor contains g-code commands that are not supported by grbl.

Try to use one of the post processors located on this page. You have to look down the page to find them.

https://discuss.inventables.com/t/xcarve-jtech-grbl-update-9-1-2017/28943

1 Like
7

Grbl version

grbl settings
grbl settings400×599 6.12 KB

8

I downloaded and used the Xcarve PP you recommended the code now goes through PicSender without issue. BUT, it keeps doing the off-on-off-on thing with my spindle. I’m going to try reflashing grbl next to see what happens.

9

Your $32 is set to one which is laser mode. There are some “safety mode” changes that went in with the addition of laser mode to 1.1f

These “safety mode” issues can be confusing and sometimes require changes to the CAM program to work “nicely” with them.

If you are really working with a laser then I would recommend that you download my 1.0c which will give you more consistent and faster results.

If you are just using a spindle then turn laser mode off $32=0

10

!@#$ How did I not see that!?!?!?!
It’s working fine now with the different PP & the grbl setting change.
I was using your version at first but in the spirit of “if it ain’t broken,fix it” I did the upgrade. I will be moving back shortly.

Thank you for your eyes and wisdom! Life is good again.

2 Likes